Chapter 31: Using Weldments
- Using the Display/Delete Relations tool, delete all the Equal relations that you just
added to the part (it may be faster to select Undo from the File menu or press
Ctrl+Z).
- Draw a vertical construction line from the part Origin to the point where the four
lines meet, and assign this line an AlongY relation. Notice that the point drags much
more smoothly. This is a good reason for using simpler relation schemes when possible.
The four equal relations in this case that had to be solved simultaneously are now
replaced by a single relation that is easier to solve when you drag the sketch. Apply a
dimension of 80 inches to the new construction line.
- Draw a new line from the point where the four lines come together AlongX in the
positive X direction. Dimension this new line as 120 inches. The sketch should now
look like Figure 31.24.
FIGURE 31.24
The sketch after Step 16
- Exit the sketch. Click the Structural Member toolbar button on the Weldments toolbar.
In the Standard drop-down list in the Structural Member PropertyManager, select
Custom. In the Type drop-down list, select Pipe. In the Size drop-down list, select
P-Pipe10in. This is the name that corresponds to the way the library feature part was
saved in Step 5.
- In the Path Segments selection box, select the original four sides of the rectangle. In
the Settings panel, make sure that the Apply corner treatment option is turned selected
and that the End Miter icon is selected. This is shown in Figure 31.25. Accept the com-
mand when you are done.
