SolidWorks 2010 Bible

Chapter 4: Creating Simple Parts, Assemblies, and Drawings

To cut slots in your part, follow these steps:

1. In this case, use the Centerpoint Straight Slot option. Slots are easiest to create with
   the Click-click method rather than Click+drag. Click near where you want the center of
   the slot. Click again for the center of one end; then click a third time for the width/end
   radius. The Slot PropertyManager is shown in Figure 4.12.

Create a horizontal sketch relation between the origin and the center point of the slot.
Add dimensions as shown in Figure 4.12.

Note

Using the Add dimensions option in the Slot PropertyManager can help you size the slot more quickly. This

does not require the Enable on screen numeric input option to be turned on. n

2. From this sketch, create an extruded cut that extrudes up to the surface of the coun-
   terbore in the holes. The through hole for the counterbored slot is also a slot, and so
   you can use the same technique.

Hole Wizard holes use either a 2D or a 3D sketch for the placement of the hole centers. You can define

the centers by simply placing and dimensioning sketch points. Starting with SolidWorks 2010, the 2D

sketch type is used by default, with the 3D sketch type only being used when you specify it in the

Positions tab of the Hole Wizard tool.

Cross-Reference

In Chapters 17 and 31, 3D sketches are discussed. Chapter 17 also gives a more detailed description of

the Hole Wizard. Chapter 22 has additional information on the display of threads. n

The following image shows a part with various types of holes created by the Hole Wizard, including

counterbored, countersunk, drilled, tapped, and pipe-tapped holes. The part is shown in section view

for clarity; however, the drilled hole is not shown in the figure.

Countersunk

Tapped Pipe tap

Counterbored

Holes created by the Hole Wizard

Hole Wizard: Using 2D versus 3D sketches