Chapter 6: Getting More from Your Sketches
FIGURE 6.15
Rolling the part back to Extrude3
Model in rolled back state
Rollback bar Rollback cursor
- Click the green check mark icon to close the Display/Delete Relations
PropertyManager.
- Right-click the graphics window and select SketchXpert; then click Diagnose.
- Using the double arrows in the Results panel, toggle through the available solutions.
All the solutions except one remove sketch relations. Accept the one solution that
removes the dimension. This is shown in Figure 6.16.The sketch no longer shows errors
in the graphics window, but it still does in the FeatureManager.
- Close the sketch. Notice that the error flag does not disappear until the sketch has been
repaired and closed.
- Use the rollback bar to roll forward to after Extrude2 and Sketch2. Figure 6.17
shows the tool tip message that appears if you place the cursor over the feature with the
error. With time, you will begin to recognize the error messages by a single keyword or
even by the shape of the message text. This message tells you that there is a dangling
relation — a relation that has lost one of the entities.
- Edit the sketch (see Figure 6.18). If you show the Sketch Relation icons again, the
errors will be easier to identify. When you use Display/Delete Relations (Tools ➪
Relations ➪ Display/Delete Relations), the first two Coincident relations appear to be
dangling. Clicking the relation in the Relations panel of the Display/Delete Relations
PropertyManager shows that one point was coincident to a line and the other point was
coincident to a point.
