Chapter 10: Working with Part Configurations
- Change the value of the number to 8, and be careful to also change the drop-down
setting to This Configuration Only instead of All Configurations. If you forget to do
this, then you will have to go to the other configuration and set it back to 6.
- Click the Rebuild symbol (which resembles a traffic light) to show the changes
before exiting the Modify dialog box. Notice that the CrvPattern2 fails after rebuilding
CrvPattern1 with eight instances. Click the green check mark icon to exit the Modify dia-
log box, and then make the same changes to the CrvPattern2: change the dimension
name and the number of patterned instances to eight (remember to use the This
Configuration Only setting). The part should now look like Figure 10.32.
FIGURE 10.32
The model after Step 9
- When you double-click to change configurations, the SolidWorks interface now
shows a part with a different color and a different number of holes and ribs. After
the first change between configurations, the changes should happen quickly because
SolidWorks has stored the geometry.
- Choose File ➪ Properties and select the Configuration Specific tab. Set the Apply To
drop-down list to Default, and type a Property Name of description and a Value of Gray
Vent Cover. Now change the Apply To drop-down setting to Size 1 and type a descrip-
tion for the new configuration using the name of the color that you applied to this config.
Figure 10.33 shows the two states of the data.
- Exit the Custom Properties dialog box. Now that you have made a few changes manu-
ally, the following steps guide you through bringing these changes into a design table and
using the design table to make additional changes.
