Chapter 21: Working with Drawing Views
The Broken View PropertyManager also enables you to set the gap size and the style of the break.
The gap refers to the gap between the break lines in the finished broken view. The setting here
overrides the default for this view only. The default setting is a template setting found in
Tools ➪ Options ➪ Document Properties ➪ Detailing. Other options that you can set in this location
are the break line extension (the distance the lines extend past the model edges) and the break line
font (on the Line Font page of the Document Properties tab). The setting that enables the broken
symbol on a dimension is found on the Dimensions page, and is named Show Dimensions As
Broken In Broken Views.You can remove individual breaks in a broken view by selecting one of the break lines and pressing
Delete. You can add breaks by applying the Break command and adding more breaks to a view. You
can alter breaks by simply dragging the break lines. In past versions, it was possible to get the view
very confused by dragging one set of breaks to interfere with another set of breaks. That problem
has been fixed by not allowing break lines to be dragged past one another.Starting with SolidWorks 2009, broken views now enable you to dimension the break lines them-
selves so that when the model changes, you can control the location of the break lines relative to
part geometry.Consider using the Unbreak option from the RMB menu to temporarily unbreak a view to make
dimensioning more convenient.Auxiliary View
An Auxiliary View is a view that is projected from a non-orthogonal edge. This type of view is often
necessary to view features (such as holes drilled at an angle) square on, so that they appear circular
in the view rather than foreshortened and elliptical. An Auxiliary View is shown in Figure 21.20 in
the image to the left. If the edge that the view was created from is updated, then the Auxiliary View
will reorient itself. The image to the right shows an Auxiliary View projected from an arbitrarily
drawn sketch line. The line or edge used to project an Auxiliary View cannot be reselected; how-
ever, if a sketch is used to project the view, then the Edit Sketch option is available through the
view arrow RMB menu.
Alternate Position View
The Alternate Position View is only available for views of an assembly and shows the assembly in
two different positions (not from different viewpoints; this requires an assembly that moves). This
is another view type that does not create a new view, but alters an existing view. Figure 21.21
shows the PropertyManager interface for the Alternate Position View, a sample view that it creates,
and the way that it is represented in the drawing FeatureManager.