Chapter 22: Using Annotations and Symbols
- Click inside the isometric view; then on the Annotation tab of the Commend
Manager, click the Auto Balloon icon. This places balloons on all the parts. Drag the
cursor to place them a comfortable distance from the parts, but still inside the view.
Accept the Auto Balloon by clicking the green check mark icon.
- Click on one of the balloons, and try to reconnect the arrow to a different location
on a different part. Notice the number in the balloon changes. If the balloon won’t relo-
cate to the face of a part, drag it to an edge. You can even drag the attachment point to
another part in another view. Leave the balloon attached to one of the pipes coming out
of the assembly in the isometric view. The balloon should have the number 2 in it.
- With the balloon used in the last step still selected, use the Balloon
PropertyManager, shown in Figure 22.19. Click the box next to Quantity, and notice
“2 X” shows up next to the balloon. Try some of the Placement and Denotation options to
see what you prefer.
FIGURE 22.19
Displaying a quantity next to a balloon
- Click the Note icon on the Annotation tab of the CommandManager. Click the cursor
in a white area of the drawing near the isometric view to place a note. Type THE PIPE IS
THE INLET. Use the lower-right handle of the text box to resize the note so that it is dis-
played in two lines.
- Place the cursor between the words THE PIPE, and click the balloon with the 3 in
it. This places the balloon inside the text. See Figure 22.20.
- Type another note in empty space on the drawing that says, for example, “This is
another use of the balloon.” With the text box still active, clear the highlighting and
then re-highlight only the word “use.” In the PropertyManager, expand the Border panel,
and select Circular from the top drop-down list. This puts a balloon around the word
“use.”
