Mechanical APDL Structural Analysis Guide

1. Choose menu path Main Menu> Preprocessor> Element Type> Add/Edit/Delete. The Element
   Types dialog box appears.


2. Click Add. The Library of Element Types dialog box appears.


3. In the scroll box on the left, click on "Structural Beam" to select it.


4. In the scroll box on the right, click on "2 Node 188" to select it.


5. Click OK.The Library of Element Types dialog box closes.


6. Click Options in the Element Types dialog box.


7. Choose Element Behavior K3 : Cubic Form. Click OK.


8. Click Close in the Element Types dialog box.

7.6.3.3. Define the Real Constants and Material Properties

1. Choose menu path Main Menu> Preprocessor> Sections> Beam> Common Sections. The BeamTool
   dialog box appears.


2. Enter .5 for B and .5 for H.


3. Click OK.


4. Choose menu path Main Menu> Preprocessor> Material Props> Material Models. The Define Material
   Model Behavior dialog box appears.


5. In the Material Models Available window, double-click on the following options: Structural, Linear, Elastic,
   Isotropic. A dialog box appears.


6. Enter 30e6 for EX (Young's modulus), and click on OK. Material Model Number 1 appears in the Material
   Models Defined window on the left.


7. Choose menu path Material> Exit to remove the Define Material Model Behavior dialog box.

7.6.3.4. Define Nodes and Elements

1. Choose menu path Main Menu> Preprocessor> Modeling> Create> Nodes> In Active CS. The Create
   Nodes in Active Coordinate System dialog box appears.


2. Enter 1 for node number.


3. Click Apply. Node location defaults to 0,0,0.


4. Enter 11 for node number.


5. Enter 0,100,0 for the X,Y, Z coordinates.

Release 15.0 - © SAS IP, Inc. All rights reserved. - Contains proprietary and confidential information

Buckling Analysis