Mechanical APDL Structural Analysis Guide

8. Choose menu path Main Menu> Solution> Solve> Current LS.


9. Carefully review the information in the status window, and click on Close.


10. Click OK in the Solve Current Load Step dialog box to begin the solution.


11. Click Close in the Information window when the solution is finished.

7.6.3.8. Review the Results

1. Choose menu path Main Menu> General Postproc> Read Results> First Set.


2. Choose menu path Main Menu> General Postproc> Plot Results> Deformed Shape. The Plot Deformed
   Shape dialog box appears.


3. Click the "Def + undeformed" option on. Click OK.The deformed and undeformed shapes appear in the
   ANSYS graphics window.

7.6.3.9. Exit ANSYS

1. In the ANSYS Toolbar, click on Quit.


2. Choose the save option you want and click on OK.

7.7. Sample Buckling Analysis (Command or Bat ch Method)

You can perform the example buckling analysis of a bar with hinged ends using the ANSYS commands
shown below instead of GUI choices. Items prefaced by an exclamation point (!) are comments.

/prep7

et,1,188

keyopt,1,3,3

sectype,1,beam,rect

secdata,0.5,0.5

mp,ex,1,30e6

mp,prxy,1,0.3

n,1,0,0,0

n,11,0,100,0

fill,1,11,9, , ,1,1,1,

e,1,2

egen,10,1,1

finish

/solu

nsel,s,node,,1

d,all,uy,,,,,rotz

allsel

nsel,s,node,,11

d,all,ux

f,all,fy,-1

allsel

dsym,symm,z

rescontrol,linear,all,1

solve

finish

/solu

antype,static,restart,,,perturb

Release 15.0 - © SAS IP, Inc. All rights reserved. - Contains proprietary and confidential information

Sample Buckling Analysis (Command or Batch Method)