Introduction to SolidWorks

Lesson 7 – Modeling the Truck
Section III – Modeling Complex Parts 7.3 Modeling the Truck

 A new plane is created that is rotated

from the Front Plane 30 degrees

using the shaft axis for rotation. See

Figure 7.4.

Step 49: Create another plane parallel to the
rotated plane.

 Click InsertReference Geometry

Plane.

 For the First Reference click the

plane that we created in the previous

step.

 Click the Offset distance icon to

create a parallel plane 1.15 inches

away.

 Click OK.

 Notice that rotation requires two

references while offset needs only one.

Step 50: Create the base of the dome at the tip of the truck pivot.

 Verify that the new offset plane is active. Its color is different from other visible planes.

 In the Heads-up View toolbar, click on View Orientation and select Normal To. The

view can be rotated 180 degrees by clicking View OrientationNormal To a second

time.

 Sketch a circle on the new plane as shown in Figure 7.5.

 The center of the circle is

the origin.

 Notice that the origin is

not on this plane, but if

you move the cursor over

the blue coordinates,

Inferencing will show the

location of the origin. If

the blue coordinates are

not visible, click View in

the Command Manager

and verify that the check

mark next to Origins is

visible.

 Also notice that the

diameter of the circle is 0.4 inch because it must match the dome of radius 0.2 inch.

Figure 7. 4 – Front, Rotated and Parallel Planes

Figure 7. 5 – Sketch for Pivot Tip